🎉Community Raffle - Win $25

An exclusive raffle opportunity for active members like you! Complete your profile, answer questions and get your first accepted badge to enter the raffle.
Join and Win

Problem: Plastic strain results do not match with the Von Mises stress results.

User: "Altair Forum User"
Altair Forum User
Altair Employee
Updated by Altair Forum User

Hi all,

 

I'm getting very low plastic strain results in my simulations. the Von mises stress (422 MPa) clearly passes the yield point (355 MPa), however plastic strain only reaches a value of 0,008. This Von mises value approaches the UTS value of 455 MPa, the strain at uts is defined as 0,09. Can someone please explain to me how i can solve this, or explain why this is happening?

 

materiaal_Definitie.JPG.1f7a4f035a9bbb5c3c0d61601260ac3f.JPG

<?xml version="1.0" encoding="UTF-8"?>1871648011_VonMises.thumb.jpg.f55da6f263efe4327e83817706c407da.jpg

 

<?xml version="1.0" encoding="UTF-8"?>Plastische_rek.jpg

Unable to find an attachment - read this blog

Find more posts tagged with

English
Radioss
Sort by:
1 - 2 of 21
    User: "Andy_20955"
    Andy_20955
    New Altair Community Member
    Updated by Andy_20955

    Hi,

    With LAW2, Iflag=1 the UTS and strain at UTS are engineering strain values.    But the output by Radioss is true stress and strain.  If you look in the Radioss starter you can see the Iflag=0, a, b, n values that are calculated using your input. 

      

     JOHNSON COOK MODEL :      YIELD STRESS  . . . . . . . . . . . . .=  355.0000000000          ULTIMATE STRESS (UTS) . . . . . . . . .=  470.0000000000          STRAIN AT UTS (Ag). . . . . . . . . . .= 9.0000000000000E-02      YIELD COEFFICIENT A . . . . . . . . . .=  355.0000000000          YIELD COEFFICIENT B . . . . . . . . . .=  312.9879880695          YIELD COEFFICIENT N . . . . . . . . . .= 0.2806664576242          EPS-MAX . . . . . . . . . . . . . . . .= 0.2100000000000          SIG-MAX . . . . . . . . . . . . . . . .= 1.0000000000000E+30      ISO-KINEMATIC HARDENING FACTOR. . . . .=  0.000000000000

     

    You can input the a, b, n value into the equation in the comments of LAW2.  image.png  Note this equation is true stress as a function of plastic strain and I have left off the temperature and strain rate terms.

     

    Or the pre-processor HyperCrash lets you plot a material when you use a, b, n in LAW2.

     

    screenshot.699.png

     

    Note that this is a plot of True stress versus true strain (not plastic strain). 

     

    Please check if your output makes better sense using these stress strain plots. 

     

    It is good that you are thinking about the results with respect to your material input to see if they make sense.  Not everyone does this but they should!

     

    Thanks,

    Andy

     

    User: "Altair Forum User"
    Altair Forum User
    Altair Employee
    OP
    Updated by Altair Forum User

    Hi Andy,

    Thank you for you're response and insight.

     

    So it could be that the plastic strain of 0,008 is realistic. When I calculate the stress with the JC formula, I get a true stress value of 435 MPa at a plastic strain of 0,008. Which could match the true stress strain plot. 

    Could you tell me how the Plastic strain is calculated for post processing purposes?

     

    Thanks,

    Cedric

Quick Links